Two suppliers quote the same bracket. One comes back at 0.42 per piece and the other at 0.55, and the difference is rarely the press or the hourly rate. It comes from how many operations each supplier decided the bracket needs, and in what order those operations run.
Process selection in stamping means one thing at the tool design table: the sequence. Each station does one job, the strip advances by one pitch, and the part carries the result of every earlier station into the next one. Piercing, notching, forming, coining, drawing, trimming and cut-off are distributed along that line, and the die type follows from how the distribution turns out.
1) The part decides the sequence. Geometry, thickness and tolerance set which operations are possible and how many passes the material can take.
2) Order carries as much weight as the operation itself. Piercing before forming and piercing after forming produce two different parts from one drawing.
3) Stations drive tooling cost harder than anything else on the quote. The number of stations sits second only to part complexity in the tooling cost list.
4) Volume decides how many stations you can justify. It does not decide which shapes the press can produce.
Two shops can both quote progressive die stamping and still build different tools, one with seven stations and one with twelve. The larger die holds a different tolerance stack and leaves a different scrap pattern behind. Neither answer is wrong, because they answered different questions.
Nobody plans a poor sequence. It happens when a price is prepared before the part has been mapped from features to operations.
A drawing carries hundreds of dimensions and usually only a handful of real features. Sorting the part into those features is the first step of process selection, because features map to operations far more directly than dimensions do.
1) Pierced features
Holes, slots and apertures, including very small holes relative to thickness.
2) Bend lines
Straight bends, offsets and hems, each with a radius the material can accept.
3) Local forming
Ribs, embossments, lances and stops that stiffen or locate without cutting.
4) Drawn volumes
Cups, pockets and housings where sheet flows into a cavity instead of bending.
5) Coined or flattened faces
Bosses, seats and calibration passes that set a dimension after forming.
6) Edge condition
Which edge is functional, how much burr is allowed and which side it may sit on.
The edge condition is the feature that goes missing most often between engineering and purchasing. That omission alone decides whether conventional blanking is enough or whether the route has to include fine blanking.
| Feature on the drawing | What the sequence has to give it | What it constrains |
|---|---|---|
| Hole pattern with position tolerance | Pilot holes pierced before any forming station | Station count, because pilots need their own punch and their own place on the strip |
| Drawn cup with a flat flange | Blank holder control and often more than one draw pass | Press tonnage, die height and the die type itself |
| Functional sheared edge | Smooth shear across most of the thickness | Whether a fine blanking press enters the route |
Feature mapping takes an hour. Skipping it moves the same conversation to the sample approval meeting, where the options have narrowed to rework or a new tool.
Every stamping sequence is assembled from a short list of operations. Knowing what each one does to the material explains why some of them share a stroke and others refuse to.
| Operation | What it does | Where it belongs in the sequence |
|---|---|---|
| Piercing | Cuts holes and slots through the strip | Early, and before any forming that could move them |
| Blanking and trimming | Cuts the outside profile, either free of the strip or after forming | Late, once the carrier no longer has to hold shape |
| Bending | Folds the material along a line to an angle | After piercing, before cut-off |
| Forming | Draws ribs, offsets and reliefs without cutting | Middle stations, while the part is still carried |
| Drawing | Pulls sheet into a cavity so the wall becomes a hollow shape | Its own pass or passes, with the flange held |
| Cut-off | Separates the finished part from the carrier | The last working station |
| Feeding and piloting | Advances the strip and re-datums it against the tool | Every stroke, not a station you can skip |
Cutting operations travel well together. Two or more of them can happen in the same press stroke, which is exactly what a compound die does, and the part leaves that stroke with its hole pattern and its outline cut in one hit. Forming operations behave differently, because each one changes the shape of the strip and the position of everything downstream.
A flat part is a cutting problem. A part with depth is a forming problem that also needs cutting.
Take a bracket with two holes, a 90 degree bend and a trimmed outline. Both sequences below use the same press, the same material and the same three operations, and only one of them holds the hole position after the bend.
1) Notch the strip outline
2) Bend the 90 degree flange
3) Pierce the two holes into the formed part
The bends are in place before the holes are cut, so the punch meets a surface that is no longer flat. Hole position now depends on how the flange sprang back at step 2.
1) Pierce the two holes plus a pilot
2) Notch the strip outline
3) Bend the flange, using the pilot to re-datum the part
The holes are cut while the strip is still flat, and the pilot holds their position through the bend. Springback still moves the flange, but the hole pattern survives it.
Sequence B is the one that reaches production: cut the datums first, form against them, release the part last.
1) Pilot holes go first. They locate every station that follows, and a conical pilot entering a pre-pierced hole corrects feed error before the forming punches close.
2) The outline is cut late enough to keep the carrier stiff. Trim too early and the remaining web cannot pull the part through the rest of the tool.
3) Coining and flattening follow forming. A calibration pass before the bend has nothing to calibrate.
4) Anything that changes strip length runs before the station that measures position. Draw a pocket first and the pitch you set at the feed rolls no longer matches the pitch inside the die.
Putting a forming station ahead of a piercing station moves holes that were already correct, and no amount of inspection afterwards puts them back.
Tooling price is built from a short list of factors, and the number of stations sits near the top of it. A tool shop prices the punches, the plates, the guides and the assembly time that every additional station adds, and then adds the tryout hours needed to make that station behave.
Schematic ranking of tooling cost factors, in the order a tool shop feels them. A longer bar means more influence on the final price. This is a drawing, not a price model.
Product complexity
Number of stations
Material thickness
Expected production volume
Volume appears at the bottom of that list, and it still changes the answer. A tool built for 50,000 parts and a tool built for two million parts can carry the same part number, but they will not carry the same steel, the same guiding or the same maintenance plan. Lower unit cost at high volume is bought with a more expensive die, and a die that has to survive more strokes.
Two decisions sit on top of the station count. Merging two cutting operations into one stroke removes a station and saves tooling, which is the trade a compound die makes. Adding a station splits a forming job into two gentler passes and protects a tolerance that one aggressive pass would damage.
A station deleted to save tooling money usually comes back as scrap at the press, one rejected lot at a time. Merging and splitting stations is where most tooling arguments start.
The table below is the short version of the whole method. Read the left column for the shape of the part, the middle column for the operation order that makes it, and the right column for the tool that carries that order.
| Part profile | Operation sequence | Die type that carries it | Why this route |
|---|---|---|---|
| Flat washer or precision plate | Pierce the bore, blank the outside in the same stroke | Compound die | Two cutting operations share one stroke, so the bore and the profile stay concentric and the part stays flat |
| Flat bracket with holes and bends | Pierce pilots and holes, notch the outline, bend, trim, cut off | Progressive die | Several operations, one pass, no re-clamping between them |
| Large structural reinforcement | Blank the part free, transfer it, form, trim | Transfer die | The part is too big to travel on a carrier, and forming needs room around it |
| Housing, can or drawn shell | Blank, draw, redraw, trim | Deep drawing die, often multi stage | Material has to flow into a cavity, and one pass cannot absorb the depth |
| Gear, lock plate or part with a working edge | Clamp, shear under counterpressure, release | Fine blanking die | The edge itself does the working, so the smooth shear zone has to run through most of the thickness |
Rows in a table always look tidier than the parts they describe. A real bracket can need one die for a feature and a forming station for another, and the route then crosses two tools.
The factory volume guide puts prototypes on laser cutting or CNC, 100 to 5,000 pieces on a single operation die, 5,000 to 50,000 on a compound die, 50,000 and above on a progressive die, and millions of parts on high speed progressive stamping. Treat those bands as a starting point for the conversation rather than a rule, because geometry can overrule quantity in either direction.
A compound die performs two or more cutting operations during one press stroke. The common combinations are blanking with piercing and blanking with trimming, and the result is a part whose outer profile and inner features are cut before the press comes back up.
What it is good at. Dimensional accuracy between the cut features, less handling, and higher output than running the same cuts on separate dies.
Where it fits best. Flat components, washers and precision plates, at medium to high volume.
What it cannot do. A compound die is a cutting tool. Put a part that needs a drawn pocket in front of it and the route has to change.
The trade it makes. Tooling costs less than an equivalent progressive die, and the part gets one clean hit instead of two stations where the strip can shift in between.
Flatness is the argument buyers rarely hear. A part pierced at one station and blanked at the next travels between the two with nothing holding it flat, and thin material can pick up a bow that no downstream gauge will accept. Cutting both features in a single stroke removes that gap, which is why hole patterns that must stay flat relative to an outside profile often end up in a compound die.
Speeds quoted for compound tooling come with a size caveat. Small parts clear the die quickly, while large components take longer to exit and lower the output rate.
A progressive die puts the whole sequence inside one tool. The strip advances one station per stroke, every station works at the same time, and one finished part leaves the end of the die with each stroke once the strip is loaded.
1) Early stations cut the datums. Pilot holes and internal features are pierced first, because everything downstream is positioned against them.
2) Middle stations form the shape. Bending, drawing and forming happen while the part is still attached to the carrier, where it has something to hold it.
3) Late stations set dimensions. Coining, embossing, re-striking and flattening land close to the end, once the geometry has stopped moving.
4) The last station releases the part. Cut-off happens after every other feature exists.
5) The carrier is sized for transport, not for scrap. A carrier at least twice the material thickness is the common starting guideline, and it has to stay wide enough to pull the part through the forming stations.
6) Feeding is part of the process, not an accessory. The strip lifts slightly after each stroke to break the oil seal before the feed rolls advance it, and the pilots then correct whatever the feed left behind.
A progressive die does not average errors out. Every station inherits the position it was handed by the one before it, so a feed error at station three is still there at station nine unless a pilot corrects it. That is why the feeding system and the pilot design get argued about as much as the forming stations do.
Case in one line: a 700 mm reinforcement plate for a vehicle body, too wide to travel on a carrier, formed in four stations by a transfer die after the blank is cut free at the first station.
A transfer die separates the workpiece from the strip in the early stages, then moves the individual part from station to station with a mechanical transfer system. Nothing holds the part to a carrier any more. Fingers, rails or a walking beam pick it up, place it and withdraw before the press closes.
That change solves a size problem. A carrier strong enough to drag a large panel through six forming stations would be heavy, expensive in material, and prone to tipping. Cutting the blank free first removes the transport load from the strip and hands it to the transfer system, which is built for it.
| Transfer die behaviour | Practical effect on the project |
|---|---|
| Each station has its own locating arrangement | Forming is no longer limited by what a carrier can hold, so deeper and more complex shapes become feasible |
| Large parts fit and operations combine | Structural automotive parts, reinforcement plates and heavy brackets lead the list, and a transfer line often absorbs work that would otherwise become a welding step |
On a large part, the transfer decision usually gets made for you. Once the blank is too big to carry, the choice narrows to transfer tooling or a series of separate operations with a person or a robot moving the part in between.
Deep drawing is the route for parts where sheet has to flow into a cavity instead of folding along a line. The flange is held while the punch pushes material down into the die, the wall thins as it stretches over the punch nose, and the finished shape has a closed end with no joint in it.
1.8 up to 2.3 typical limiting draw ratio for a single draw, where draw ratio is blank diameter divided by punch diameter
above 3 draw ratio reachable once the shape is split across several draw stages
15 to 25 percent thinning commonly measured at the punch nose relative to the original blank thickness
under 13 percent wall thinning ceiling used as a design guideline in published sequence work, with the heavier draws placed in the early stages
up to 30 percent of the drawing load that a blank holder may need to apply on thin blanks
Those numbers turn a drawing into a station count. A cup whose depth demands a draw ratio of 2.6 cannot be produced in one pass, so the sequence becomes draw, redraw and possibly a third pass, each with its own punch diameter, die radius and draw depth.
Draw ratio is blank diameter divided by punch diameter, and it sets how much deformation one pass asks of the material.
Blank holder force clamps the flange, and too little of it wrinkles the flange while too much tears the wall at the punch nose.
Thickness to diameter ratio decides how much holder force the blank needs, since a blank at 0.03 or above usually needs little or none.
Punch radius and die radius are the two lead-ins the material has to follow, and sharp radii raise local strain while shortening tool life.
Draw depth per stage sets how much of the total depth each pass takes, so splitting a deep part into gentler passes keeps thinning inside the limit.
Annealing between stages restores ductility, because work hardening cuts it as deformation accumulates.
Deep draw work is where process choice and material choice stop being separate arguments. Pick a grade for strength alone and the draw ratio you need may be out of reach.
Conventional blanking separates material by letting a crack run through the thickness. The edge that results has four regions, and only one of them is smooth.
| Edge region | What it is | Why a buyer should care |
|---|---|---|
| Die roll | The rounded entry on the side the tool first contacts | Reduced by fine blanking, but it does not disappear, and it shifts where the edge actually sits |
| Smooth shear zone | The burnished band created by plastic shearing | This is the usable load bearing or sealing surface, so its share of the thickness is the number that matters |
| Fracture zone | The rough region left where a crack propagated | Wide in conventional blanking, narrow under fine blanking, and a source of micro cracks under load |
| Burr and taper | Exit side burr plus the slight taper through the cut | Still present in both processes, still needs a limit written on the drawing |
Fine blanking changes how separation happens. The material is clamped firmly and counterpressure is applied from the opposite side, so the shear stays dominant across a much larger share of the thickness and the fracture zone shrinks. Tool clearance is held very tight, and the part leaves the press with an edge that needs far less secondary work.
The claim that fine blanking produces a burr free edge does not survive a metallurgical check. Edge condition still depends on material, geometry, clearance, tool radii, tool wear, lubrication and process control, and in-die or secondary edge conditioning is still used on some parts. What the process removes is the long rough fracture zone, not every edge feature.
Write acceptance criteria, not adjectives. A drawing that asks for fine blanking quality without numbers cannot be quoted properly. The usable version names the functional edge, its required dimensions, perpendicularity and flatness, the permitted die roll, the burr direction and the burr limit.
With that list on the drawing, a supplier can say whether fine blanking, conventional blanking plus finishing, machining or a mixed route is the cheaper answer.
Fine blanking suits gears, lock components and precision plates where the edge does the work. Tooling and setup cost more than conventional stamping, so the process earns its place on edge function rather than on volume.
Grade and thickness set the limits that the sequence has to live inside. The same bracket in 1.0 mm SPCC and in 2.0 mm HSLA steel will not accept the same stations, the same radii or the same bend allowance.
| Material family | Forming behaviour | What it does to the sequence |
|---|---|---|
| SPCC carbon steel | General forming, smooth surface, low cost | Straightforward piercing and bending, small bend radii are workable |
| SPCD carbon steel | Better drawing performance and ductility | Opens the door to a drawn pocket or a deeper bend in one pass |
| SPCE carbon steel | High elongation for complex forming | Lets the sequence take a harder draw before a second stage is needed |
| SUS304 and SUS316 stainless | Corrosion resistance with work hardening under strain | Bend radii move outward, and forming steps get split to limit hardening |
| AL5052 and AL6061 aluminium | Corrosion resistance and low weight, lower stiffness | Forming is easier, but springback compensation and hold down stations carry more weight |
| HSLA and spring steel | High strength per unit thickness | Thinner material carries the load, but punch stress and bend radius limits tighten |
Thickness multiplies whatever the grade already does. Every extra tenth of a millimetre raises cutting force, pushes die clearance open, increases the minimum bend radius and makes material flow harder to control in a draw. A sequence that works in 0.8 mm material and fails in 1.5 mm was built for a different thickness.
Incoming material adds one more variable to the same story. Thickness variation, coil set, residual stress, edge damage and lamination all reach the die.
Defects carry a signature. A defect pattern points back at the decision that produced it, and six patterns cover most of the arguments that reach a supplier after the first production lots.
| What you see | What it usually points to | What to put right |
|---|---|---|
| Holes turn oval after the bend | A pierce station sitting after the forming station, or a hole placed too close to the bend line | Move the pierce operation ahead of the bend and check the hole to bend distance |
| Burr height grows on one edge only | Die clearance opened on that side, or uneven punch wear | Check clearance against material type and thickness, then check punch condition |
| The part will not sit flat | The bore and the profile were cut in two different strokes with nothing holding the part between them | Bring the cutting operations into one stroke, or add hold down if the sequence has to stay split |
| Cracks at the corner radius | A radius tighter than the material and thickness allow, or too much deformation asked of one pass | Open the radius or split the forming across two gentler stages |
| Wrinkles in the flange of a drawn part | Blank holder force too low for the thickness, or material flowing faster than the holder controls it | Recalculate holder force against thickness and diameter, and check lubrication |
Three of those six come back to station order rather than to tool quality. That belongs to the conversation before a plate is cut, not to the rework discussion afterwards.
No, and it usually is not. A prototype can be laser cut or machined and then formed on simple tooling, while production may run on a progressive die. What has to stay constant is the material grade, thickness and the functional dimensions, because a prototype in a different grade proves nothing about the production part.
The honest answer comes from the feature list, not from the part description. Count the cutting operations that must be separate, add one station for each forming pass, add the pilot and cut-off stations, and the number you reach is close to the die the drawings will produce.
Fine blanking narrows the fracture zone and reduces die roll, and it can remove the need for deburring on many parts. Burr and taper still exist, and their limits belong on the drawing.
It can when the draw is shallow enough to run as one station inside the strip. Deeper draws need several passes with controlled material flow, and that work moves to a dedicated deep drawing arrangement.
A first article inspection report covering the full dimension set, hole positions, bend angles, material verification, surface finish, functional features and appearance, plus the material certificate. Dimensional reports, CMM reports, coating thickness reports and salt spray reports follow where the drawing asks for them.
A quotation can only describe what the enquiry allows. When the request names a part number, a quantity and a drawing, the reply comes back as a number. Give the supplier the feature list and the volume forecast, and the reply can come back as a route.
1) Send the revision controlled drawing and the 3D model together. Say which file wins if the two disagree, because the sequence is built from geometry.
2) Name the material grade and thickness. A grade family is not enough, since SPCC and SPCE lead to different station counts on the same shape.
3) Mark the functional features. Hole pattern, bend angles, flatness, edge condition and any dimension that the assembly cannot live without.
4) Give the full quantity picture. Prototype, first order, annual demand and expected lifetime volume, because all four push the route in different directions.
5) List the secondary operations and the finish. Tapping, welding, riveting, clinching, deburring, plating or coating change the handling steps that follow the press.
Five questions then turn the reply from a price into an engineering answer. Which operations does the route contain and in what order? How many stations does that imply? Which features drove the station count? What tolerance does each critical feature get from the process rather than from inspection? What would change in the sequence if annual volume doubled?
Where this leaves you. Volume sets how much tooling the project can absorb. Geometry and tolerance decide which operations are possible at all, and the material decides how many passes it will accept before it cracks, wrinkles or work hardens.
Ronghai Mould reviews manufacturability before quoting, so the operation sequence, the tooling route and the material choice can be discussed while changes still cost nothing. Custom OEM stamping in carbon steel, stainless steel, aluminium and copper alloys, with progressive, transfer, compound and deep draw stamping, secondary operations, finishing, inspection and export packaging handled at one factory in Qingdao.
About the Manufacturer Behind Your Stamping Sequence
Ronghai Mould is a custom OEM metal stamping manufacturer in Qingdao, China, producing parts to drawings, 3D models and samples. The factory covers engineering review and DFM, in-house tooling for customer projects, progressive, transfer, compound, deep draw and precision sheet metal stamping, secondary operations, finishing, inspection and export packaging. ISO 9001 and IATF 16949 certified, with material certificates, first article reports, CMM reports, salt spray reports and traceability records available.
Inquiry
Article Navigation
About the Manufacturer Behind Your Stamping Sequence
West side of Guangzhou North Road, Jiaozhou City, Qingdao City, Shandong Province
Copyright © 2025 Qingdao Ronghai Mould Products Co., Ltd. All Rights Reserved.
Powered by HiCheng
